Home > Community > Forums > PCB Design > Pad Seed Points

Email
* Required Fields

Recipients email * (separate multiple addresses with commas)

Your name *

Your email *

Message *

Contact Us

Cadence Contacts

Global Office Locator
Find Offices worldwide »

Sales Inquiry
Request for Product information »
Cadence Channel Partners »

Corporate Headquarters
Cadence Design Systems, Inc.
2655 Seely Avenue
San Jose, CA 95134
Phone: 408.943.1234
* Required Fields
First Name *

Last Name *

Email *

Company / Institution *

Comments: *

 Pad Seed Points 

Last post Fri, Aug 6 2010 5:49 AM by Rik Lee. 3 replies.
Started by melview1 04 Aug 2010 01:04 PM. Topic has 3 replies.
Page 1 of 1 (4 items)
Sort Posts:

  • Wed, Aug 4 2010 1:04 PM

    • melview1
    • Top 150 Contributor
    • Joined on Wed, May 20 2009
    • Shakopee, MN
    • Posts 41
    • Points 785
    Pad Seed Points Reply

    Using OrCAD PCB Designer v16.3.S009 

    I would like to know how to control the copper seed point on a particular symbol, but not the whole design.

    I have a shield over a part that has 4 pads that are all GND.  This part is on the top layer which has a GND copper pour dynamic shape.  When I smooth the shapes, it makes very odd angled connections between the pads and the pour even though my global dynamic shape thermal relief parameters are set to orthogonal.  It puts in a 5 mil relief around the pad except for 3 points at which it runs a cline from the origin of the pad to the pour.  I would like to allow the copper pour to flood to these pads without a thermal relief and therefore no odd angled lines.  However, I don't want this to happen to all of the parts on the designs that connect to GND.  I like those the way they are.

     Any ideas?  Thanks.

     

    --Mark
    • Post Points: 20

  • Wed, Aug 4 2010 1:09 PM

    • Rik Lee
    • Top 25 Contributor
    • Joined on Tue, Dec 2 2008
    • HOME, SC
    • Posts 165
    • Points 2,680
    Re: Pad Seed Points Reply

    You can add the instance property to each pin. Edit >Properties; select the pin(s) and add:

     DYN_THERMAL_CON_TYPE = FULL_CONTACT

    This will provide a full contact (no thermal ties) to each of the pins.

    • Post Points: 20

  • Thu, Aug 5 2010 3:39 PM

    • Goblin59
    • Top 50 Contributor
    • Joined on Thu, Feb 18 2010
    • Centennial, CO
    • Posts 130
    • Points 2,000
    Re: Pad Seed Points Reply

     Rik,

    Does this work in Allegro also?

    Cheers,

    Ron Scott CID+

    • Post Points: 20

  • Fri, Aug 6 2010 5:49 AM

    • Rik Lee
    • Top 25 Contributor
    • Joined on Tue, Dec 2 2008
    • HOME, SC
    • Posts 165
    • Points 2,680
    Re: Pad Seed Points Reply

     Hi Ron,

    Yes, these pin instance properties can be applied in Allegro.

       DYN_CLEARANCE_OVERSIZE =
       DYN_CLEARANCE_TYPE = DRC_VALUE/ANTI_THERMAL/NO_VOID
       DYN_FIXED_THERM_WIDTH = <overrides contraint line value>
       DYN_MAX_THERMAL_CONNS =
       DYN_MIN_THERMAL_CONNS =
       DYN_OVERSIZE_THERM_WIDTH = <in addition to your constraint line value>
       DYN_THERMAL_BEST_FIT = TRUE/FALSE
       DYN_THERMAL_CON_TYPE = FULL_CONTACT/DIAGONAL/ORTHOGONAL/8_WAY/NONE
       
       
    The following can also be applied at the shape instance level as well overriding what you have for your global dynamic shape parameters. The can be found when selecting the shape and then using the right mouse button to select shape parameters. Pin properties will override both shape instance and global paramaters.
       
       DYN_THERMAL_CON_TYPE - Can be applied differently depeing on pin type (via/smd pins/thru pins
       MIN/MAX CONNEXTIONS - Also applied per pin type
       FIXED THERMAL WIDTH
       THERMAL WIDTH OVERSIZE
       CLEARANCE TYPE - DRC/THERMAL or ANTI applied per pin type
       OVERSIZE VALUE - Applied per pin type
       
    Hope this helps,

    RIk
    • Post Points: 5
Page 1 of 1 (4 items)
Sort Posts:
Started by melview1 at 04 Aug 2010 01:04 PM. Topic has 3 replies.